PCB Design Guidelines for GPS chipset designs. Section 1. Section 2. Section 3. Section 4. Section 5
|
|
- Arron Fleming
- 6 years ago
- Views:
Transcription
1 PCB Design Guidelines for GPS chipset designs The main sections of this white paper are laid out follows: Section 1 Introduction Section 2 RF Design Issues Section 3 Sirf Receiver layout guidelines Section 4 Common problems to avoid Section 5 Summary 1. INTRODUCTION This document will present some of the critical issues that arise when laying out a new GPS design based on the SiRFstarIIe and SiRFstarIIeLP chipset. Since the RF# characteristics of the receiver are generally the most critical they will be discussed in detail followed by specific SiRF GPS layout guidelines. All new designs based on the SiRFstarIIe and SiRFstarIIeLP chipset should follow these guidelines. SiRF Applications
2 1.1 General PCB Guidelines Before discussing the critical RF concerns it is worthwhile summarizing some very basic issues when starting a new layout, since proper connector and component placement is the critical first step to generating a new design. SiRF reference designs are typically done on a 4-layer or 6-layer, 2- sided, standard FR4 board all parts should be surface mount (if possible) connector locations should be placed to avoid noisy system interconnect cables from running across the GPS board all RF components should be placed to minimize trace lengths and crossovers all power pins on all IC s should have.01uf decoupling capacitors placed as close to the IC as possible and connect directly to the power and ground planes of the board reserve space for shielding of the RF and the baseband (adequate shielding is necessary to isolate the sensitive RF section and antenna from other noise-generating circuitry) Shields should be soldered to the board, not simply tacked down. Shields require grounding at 100mil spacing. the RF and digital circuitry should be grouped in separate sections on the board all RF grounds should be directly to the ground plane using a dedicated via high pin-count digital components should be placed to minimize routing of multi-trace bus lines crystal oscillator circuits should be isolated from high slew-rate digital signals the designer should always follow the manufacturer s DFM requirements attempt to use the same components that SiRF specifies as a part of the reference design bill of materials keep the RTC section away from the digital and RF circuitry. The RTC circuitry should be routed over the ground plane if possible. Otherwise, avoid any digital signals underneath the RTC. Although very basic, if these guidelines are adhered to during the initial parts placement then a majority of the PCB related problems can be avoided. 2. RF Design Issues RF circuits present new challenges to designers of lower-frequency digital circuits. RF circuits usually deal in nano-volts and the stability of oscillators has to be in the parts-per- billion! Signals will not stay on lines they are supposed to and components do not act as they are expected to. To be able to actually build circuits correctly it is important to have an understanding of the basic properties of circuits from an RF point of view. The following section discusses some of the basic RF design issues that were addressed in developing SiRFstarI and SiRFstarIIe/IIeLP reference designs. 2.1 Tracks, Pads, and Ground Planes Most RF circuits are built over a ground plane to provide better control of parasitic coupling. All tracks, pads, and components are capacitively coupled by their physical proximity to each other. If a ground plane is used there is a large capacitive element to ground, which reduces the coupling between parts. It also provides for a well-controlled return path for currents, which helps keep signals localized. Component pads also generate a capacitance to ground, which effectively adds small capacitors to ground each time a pad is used. This is usually not a big problem for capacitors
3 greater than 100pF, but it can be if the capacitors are physically large enough. This occurs if the pads are physically large, or the dielectric (the circuit board material) is very thin. RF engineers strive to keep these capacitance s small enough to not have much effect. Unfortunately, there are other parasitic elements formed by just the copper lines on the board. Any trace over a ground plane actually forms transmission lines and should be kept as short as possible. Vias connecting through the board (to ground) will have a small amount of inductance which could be a problem for RF signals. RF signals require very good grounding. If an IC has numerous ground pins they should all be grounded separately (i.e. with their own vias) to minimize inductance. It is also possible for signals to crosstalk through common vias, so it is good practice to ground everything separately. 2.2 RF Components SiRF has designed a reference GPS receiver using our preferred component vendors but new designers may choose to substitute non-critical parts. When doing this, the RF and parasitic performance of each component should be considered. Chip Resistors- Chip resistors have many parasitic elements, but in general the resistance of the resistor masks most of these effects. The most important RF characteristic of chip resistors is the series inductance due to it s physical length. For 0603 components at GPS frequencies this is usually not a serious problem. Chip capacitors- The series inductance mentioned above for resistors is also the most important characteristic in capacitors which generally cannot be ignored. The capacitor and this inductance resonate at some frequency, and engineers have to be careful of this property. A 12 pf 0603 capacitor (with pads and trace inductance) resonates at GPS frequencies, and this can be used to bypass power lines to stop the GPS signal from going where we don t want it. It can also be used to block DC and pass GPS signals with no degradation. On the other hand a 0.1 uf chip capacitor resonates at about 30 MHz and above resonance is quite inductive, so it will not bypass signals above 100 MHz very well and this is why it is not sufficient to use this as a bypass for GPS frequencies. Chip inductors- These are the most difficult components to model. Their main parasitic component is the parallel resonance formed by their interwinding capacitance, and their own inductance. The parallel capacitance can vary widely from manufacturer to manufacturer, so if the inductor is used near it s parallel resonance, it is important to ensure that any inductor from a new manufacturer is similar to the original. Usually the only time this parallel resonance is used is to act as an RF open-circuit, while allowing DC to pass (such as in bias-t s when it is needed to introduce DC into an RF cable). Inductors of the 0603 size, and with a very small number of turns can cause wide variations in circuit performance, especially when different manufacturer s inductors are compared. If the inductor is used in a matching network there may be large variations in RF performance depending on how the inductor is built, and how it is mounted. It is also important to minimize noise coupling into inductors by either shielding them or placing them as far away from the noise sources as possible. 2.3 Gain, Stability, and By-Passing Too much gain at RF frequencies is hard to control and can cause stability problems if not managed correctly. The GPS signal at MHz is hard to keep stuck on traces, even using a ground plane. Each of the components acts as small antennas that can talk to each other and cause amplifiers to oscillate. A general rule to control this is to keep gain at any one
4 frequency below about 25 db. If this is not possible, it will be necessary to place a shield over the circuitry to reduce unwanted feedback. The SiRFstar typical reference design uses a single 15dB gain stage in front of the GRF2i/GRF2iLP and a single shield over the entire RF section. It is important to keep all RF signals off the power lines. If RF signals get onto the power lines then circuits can oscillate, or misbehave in other ways. Series resonant capacitors can be used to bypass the power, but they are only good at one frequency and therefore broadband bypassing techniques should be used. If it is necessary to stop more than one frequency it is possible to use 2 different capacitors (e.g..01uf and 100pF), but there is a drawback. Above the resonance of the large capacitor it will look inductive, while the smaller capacitor is still capacitive. This can form a parallel resonator that actually performs worse for frequencies between the two individual resonant frequencies. If it is possible to put a resistor, ferrite bead, or inductor between the two capacitors then it is possible to fashion a better bypass than that made with the two capacitors alone. Ferrite beads have very complicated equivalent circuits, so it is important to understand them before using them. There are many different types that act quite differently. The typical one used in the 0603 size is usually like a parallel resonant inductor, and becomes a resistive element at GPS frequencies. This can make for a fairly good element for a bypass network, when paired with suitable capacitors. There are currently a number of chip components available that look like a capacitor, but also have a grounded center pin. These are feedthrough capacitors, and are very good for bypassing signals. 2.4 Crystal Oscillator Requirements The crystal oscillator needs to have very little noise on it in a GPS system and also not vary too much over temperature. It is therefore critical that the crystal be placed very near the oscillator IC could and be isolated from noise-generating circuits. It should also be placed away from IC s that dissipate a lot of power which can cause large temperature gradients at turn-on. In a GPS receiver, the system can track oscillators that vary smoothly over 10 to 15 parts per million (ppm), but if the oscillator signal is jittering back and forth (even as little as 5 parts per billion), the receiver will have trouble. Therefore it is necessary to keep the oscillator as clean as possible. Short traces, and careful layout, keeping any signal, especially digital ones, away from the circuitry, are important. The oscillator will also be prone to proximity effects, such as waving your hand near it, therefore it should always be shielded! To avoid your GPS crystal oscillator from affecting your sensitivity, ensure that your filter on the output of the GPS crystal is sufficient enough to reduce the drive level of Xtalin to <350mVpp. It has been discovered that at very high drive levels, the doubler in the RFIC will produce side bands due to jitter. This in turn causes the sensitivity of the receiver to degrade by as much as several db. For further information, please speak with your SiRF application engineer. 2.1 RF Power Supply Another source of noise is from the power supply. Ensure the supply is well bypassed for both low and high frequencies. The oscillator generally needs a linear-regulated supply voltage to function well enough in a GPS system. The combination of a good linear regulator and good bypassing ensures that the oscillator supply is as clean as it can be. For bypassing, you only require one tantalum capacitor as close to the regulator output as possible. Additional
5 capacitors will have little or no effect. Also, when routing the regulator output traces, the thicker the power trace from the regulator to the RFIC, the better the performance. 3. SiRF Receiver Layout Guidelines 3.1 PCB Fabrication Requirements On our SiRFstarI and S2AM reference designs we used a standard 4-layer,.062in FR4 PCB with no special controlled-impedance requirements. This is possible if all RF routing is kept as short as possible (to avoid transmission line effects). When routing signals at MHz, if the track length must be longer than about 0.1in, then its width should be chosen to implement a 50ohm microstrip transmission line. All other non-critical routing was with 5mil lines with 5mil spacing using 12mil diameter vias. Because RF performance can be sensitive to pad capacitance, the inner-layer dielectric spacing is critical and should adhere to the 8mil spec (between layer 1-2). If board size is critical then a new design should consider using a 6-layer board and possibly 0402 chip components (although both of these increase cost). With our S2AR SiRFstar IIe reference designs, we used a 6-layer,.062 FRF PCB. You can refer to our S2AR reference design for further info on routing and hole sizes. 3.2 Placement of Components As can be seen from our reference designs, the RF and digital sections are naturally separated. In our 4 layer designs, the RF section is completely shielded and no digital components (or routing) were placed beneath it. In our 6 layer designs, the RF section is on one side, while the digital is kept to the backside. We avoid routing noisy digital lines under our GPS and RTC clocks, as well as our RF loop filter. With all of our reference designs, we attempt to keep the PECL interfaces between the baseband and RF chip, short and straight. If you are required to route the PECL lines around other components/traces, ensure that you change direction at 45 degree angles. Implementing long run PECL s with multiple direction changes can lead to low drive levels to the baseband as well as increase the chances of picking up noise. As an option, you may also want to consider placing a small resistor pack in line with each PECL interface for better noise immunity. The actual resistor value utilized is somewhat dependent on the spacing between the RF and baseband and is typically 1k ohm for very short distances and about 100 ohms for longer distances Layer Stacking With respect to 4 layer designs, we recommend the following: Note: For in-depth information, refer to the S2AM reference design, as well as application note #21. Layer 1 is the component (i.e. top) side where SiRF places the baseband and flash memory (from the digital section) alongside the RF chip. The entire RF section is shielded with a small hole in the top to attach an RF cable. Layer 2 is the ground plane. It should be placed directly below the RFcomponents for best isolation. SiRF uses a common ground plane for the digital and RF sections. We highly recommend that you do not split your ground planes. One common ground for the RF and digital should suffice.
6 Layer 3 is a power plane with typically two different Vcc voltages. The RF section runs on 2.85v while the digital circuits run mostly off of 3.3v. For upgrading to the SiRFstarIIeLP, you may also require the addition of a 1.8V plane, but this can be avoided very easily. We do not recommend any other signal routing in this plane. Layer 4 is typically the solder side where additional memory and non-critical components are usually placed. No digital circuits should be placed under the RF section. With respect to 6 layer designs, we recommend the following: Layer 1 is the component (i.e. top) side where SiRF placed the entire RF circuitry, from the SiRF RF chip to the RF regulator. The entire RF section is shielded with a small hole in the top to attach an RF cable. Layer 2 is the ground plane. It should be placed directly below the RF components for best isolation. SiRF uses a common ground plane for the digital and RF sections. We highly recommend that you do not split your ground planes. One common ground for the RF and digital should suffice. Layer 3 and 4 are inner signal routing. This area should be used for routing all digital signals which interface to memory, reset supervisor s, etc. Do not route any RF signals in the inner layers. Layer 5 is a power plane with typically two different Vcc voltages. The RF section runs on 2.85v while the digital circuits run mostly off of 3.3v. For upgrading to the SiRFstarIIeLP, you may also require the addition of a 1.8V plane, but this can be avoided very easily. We do not recommend any other signal routing in this plane. Layer 6 is utilized as the baseband, memory and supporting circuitry layer. If feasible, try to avoid routing any digital components directly under the GPS crystal. 3.3 Routing Issues With proper component placement routing can usually be straight-forward. A few items to adhere to during routing are; keep all digital lines away from the RF section avoid routing between components (to prevent undesirable coupling) RF routing longer than about.1in should be 50ohm transmission lines RF and bypass grounding should be direct to the ground plane through its own via Isolate the digital noise from the RF section by using separate ground and power planes. This can be quite useful, but care must be taken in how the power and ground signals cross the gap between the two sections. For simplicity and reliability, we recommend using one uniform ground plane. Usually all signal and power lines are bypassed as well as possible, and the ground is connected with a trace at a spot that has been shown to be optimum (usually near the edge of the board). In the case of the SiRF product, if you choose to split ground planes, you should connect them near the differential outputs of the RF chip. It can be quite tricky to accomplish this ground connection to satisfy all the operating conditions. Do not use an inductor or bead to connect the grounds, because when a cable is hooked up to the board a
7 great deal of 60 Hz and other radiated signals appears across this inductor, and causes the RF section to be totally jammed by noise. If the board is going to be mounted in an enclosure, noise can radiate around the split and effectively cancel out the isolation. If the whole unit is going to be shielded this also cancels out the split because the shield has to connect to both the RF and digital grounds to be effective. SiRF has found that the most practical method of building a GPS receiver is to use the same ground for both the RF and digital sections, but to build a good shield around the RF section. Manufacturability should also be considered when placing and routing components. This includes trace width, trace spacing, component spacing, tooling holes, edge-clearances, testpoints, etc.. 4. Common Problems to Avoid The most common reason for a GPS receiver not functioning (when first integrated), is because the receiver is jammed by digital noise. The receiver is so sensitive that harmonics of the digital signals are much larger than the signals being processed. It cannot be stressed too much that seemingly inconsequential design violations can cause digital noise to get into the front end and degrade system performance. Some mistakes that have caused problems in the past are: not designing the PCB with the required layer1-2 spacing allowing the RF power plane to extend beyond the RF shield passing digital signals near the RF front-end via holes passing unbypassed power into the RF section placing the IF filter inductors too close to noisy circuits routing RF ground pins using long traces using alternate components which do not have the same RF characteristics inadequate shielding long PECL interface between the RF and BB not bypassing any digital outputs to the outside world with 12pF capacitors
PI3DPX1207B Layout Guideline. Table of Contents. 1 Layout Design Guideline Power and GROUND High-speed Signal Routing...
PI3DPX1207B Layout Guideline Table of Contents 1 Layout Design Guideline... 2 1.1 Power and GROUND... 2 1.2 High-speed Signal Routing... 3 2 PI3DPX1207B EVB layout... 8 3 Related Reference... 8 Page 1
More informationChapter 16 PCB Layout and Stackup
Chapter 16 PCB Layout and Stackup Electromagnetic Compatibility Engineering by Henry W. Ott Foreword The PCB represents the physical implementation of the schematic. The proper design and layout of a printed
More informationThe number of layers The number and types of planes (power and/or ground) The ordering or sequence of the layers The spacing between the layers
PCB Layer Stackup PCB layer stackup (the ordering of the layers and the layer spacing) is an important factor in determining the EMC performance of a product. The following four factors are important with
More informationClass-D Audio Power Amplifiers: PCB Layout For Audio Quality, EMC & Thermal Success (Home Entertainment Devices)
Class-D Audio Power Amplifiers: PCB Layout For Audio Quality, EMC & Thermal Success (Home Entertainment Devices) Stephen Crump http://e2e.ti.com Audio Power Amplifier Applications Audio and Imaging Products
More informationAntenna Matching Within an Enclosure Part II: Practical Techniques and Guidelines
Antenna Matching Within an Enclosure Part II: Practical Techniques and Guidelines By Johnny Lienau, RF Engineer June 2012 Antenna selection and placement can be a difficult task, and the challenges of
More informationHardware Design Considerations for MKW41Z/31Z/21Z BLE and IEEE Device
NXP Semiconductors Document Number: AN5377 Application Note Rev. 2, Hardware Design Considerations for MKW41Z/31Z/21Z BLE and IEEE 802.15.4 Device 1. Introduction This application note describes Printed
More informationApplication Note AN-00502
Proper PCB Design for Embedded Antennas Application Note AN-00502 Introduction Embedded antennas are ideal for products that cannot use an external antenna. The reasons for this can range from ergonomic
More informationABA GHz Broadband Silicon RFIC Amplifier. Application Note 1349
ABA-52563 3.5 GHz Broadband Silicon RFIC Amplifier Application Note 1349 Introduction Avago Technologies ABA-52563 is a low current silicon gain block RFIC amplifier housed in a 6-lead SC 70 (SOT- 363)
More informationMC-1010 Hardware Design Guide
MC-1010 Hardware Design Guide Version 1.0 Date: 2013/12/31 1 General Rules for Design-in In order to obtain good GPS performances, there are some rules which require attentions for using MC-1010 GPS module.
More informationHT32 Series Crystal Oscillator, ADC Design Note and PCB Layout Guide
HT32 Series rystal Oscillator, AD Design Note and PB Layout Guide HT32 Series rystal Oscillator, AD Design Note and PB Layout Guide D/N:AN0301E Introduction This application note provides some hardware
More informationApplication Note 5011
MGA-62563 High Performance GaAs MMIC Amplifier Application Note 511 Application Information The MGA-62563 is a high performance GaAs MMIC amplifier fabricated with Avago Technologies E-pHEMT process and
More informationCommon myths, fallacies and misconceptions in Electromagnetic Compatibility and their correction.
Common myths, fallacies and misconceptions in Electromagnetic Compatibility and their correction. D. A. Weston EMC Consulting Inc 22-3-2010 These are some of the commonly held beliefs about EMC which are
More informationCourse Introduction. Content: 19 pages 3 questions. Learning Time: 30 minutes
Course Introduction Purpose: This course discusses techniques that can be applied to reduce problems in embedded control systems caused by electromagnetic noise Objectives: Gain a basic knowledge about
More informationPART MAX2605EUT-T MAX2606EUT-T MAX2607EUT-T MAX2608EUT-T MAX2609EUT-T TOP VIEW IND GND. Maxim Integrated Products 1
19-1673; Rev 0a; 4/02 EVALUATION KIT MANUAL AVAILABLE 45MHz to 650MHz, Integrated IF General Description The are compact, high-performance intermediate-frequency (IF) voltage-controlled oscillators (VCOs)
More informationTexas Instruments DisplayPort Design Guide
Texas Instruments DisplayPort Design Guide April 2009 1 High Speed Interface Applications Introduction This application note presents design guidelines, helping users of Texas Instruments DisplayPort devices
More informationApplication Note 5012
MGA-61563 High Performance GaAs MMIC Amplifier Application Note 5012 Application Information The MGA-61563 is a high performance GaAs MMIC amplifier fabricated with Avago Technologies E-pHEMT process and
More informationMC-1612 Hardware Design Guide
LOCOSYS Technology Inc. MC-1612 Hardware Design Guide Version 1.0 Date: 2013/09/17 LOCOSYS Technology Inc. 1 General Rules for Design-in In order to obtain good GPS performances, there are some rules which
More informationApplication Note 1360
ADA-4743 +17 dbm P1dB Avago Darlington Amplifier Application Note 1360 Description Avago Technologies Darlington Amplifier, ADA-4743 is a low current silicon gain block RFIC amplifier housed in a 4-lead
More informationLow Jitter, Low Emission Timing Solutions For High Speed Digital Systems. A Design Methodology
Low Jitter, Low Emission Timing Solutions For High Speed Digital Systems A Design Methodology The Challenges of High Speed Digital Clock Design In high speed applications, the faster the signal moves through
More information2. Design Recommendations when Using EZRadioPRO RF ICs
EZRADIOPRO LAYOUT DESIGN GUIDE 1. Introduction The purpose of this application note is to help users design EZRadioPRO PCBs using design practices that allow for good RF performance. This application note
More informationHigh Speed Clock Distribution Design Techniques for CDC 509/516/2509/2510/2516
High Speed Clock Distribution Design Techniques for CDC 509/516/2509/2510/2516 APPLICATION REPORT: SLMA003A Boyd Barrie Bus Solutions Mixed Signals DSP Solutions September 1998 IMPORTANT NOTICE Texas Instruments
More informationDifferential-Mode Emissions
Differential-Mode Emissions In Fig. 13-5, the primary purpose of the capacitor C F, however, is to filter the full-wave rectified ac line voltage. The filter capacitor is therefore a large-value, high-voltage
More informationReference Guide RG-00110
Amplified HumPRO TM Series RF Transceiver PCB Layout Guide Introduction The Amplified HumPRO TM Series RF transceiver module has obtained a modular approval from the United States FCC and Industry Canada.
More informationAN4819 Application note
Application note PCB design guidelines for the BlueNRG-1 device Introduction The BlueNRG1 is a very low power Bluetooth low energy (BLE) single-mode system-on-chip compliant with Bluetooth specification
More informationLM2462 Monolithic Triple 3 ns CRT Driver
LM2462 Monolithic Triple 3 ns CRT Driver General Description The LM2462 is an integrated high voltage CRT driver circuit designed for use in color monitor applications. The IC contains three high input
More informationPCB Design Guidelines for Reduced EMI
PCB Design Guidelines for Reduced EMI Guided By: Prof. Ruchi Gajjar Prepared By: Shukla Jay (13MECE17) Outline Power Distribution for Two-Layer Boards Gridding Power Traces on Two-Layer Boards Ferrite
More informationThe shunt capacitor is the critical element
Accurate Feedthrough Capacitor Measurements at High Frequencies Critical for Component Evaluation and High Current Design A shielded measurement chamber allows accurate assessment and modeling of low pass
More informationMPC5606E: Design for Performance and Electromagnetic Compatibility
Freescale Semiconductor, Inc. Document Number: AN5100 Application Note MPC5606E: Design for Performance and Electromagnetic Compatibility by: Tomas Kulig 1. Introduction This document provides information
More informationMINIMIZING EMI EFFECTS DURING PCB LAYOUT OF Z8/Z8PLUS CIRCUITS
APPLICATION NOTE MINIMIZING EMI EFFECTS DURING PCB LAYOUT OF Z8/Z8PLUS CIRCUITS INTRODUCTION The Z8/Z8Plus families have redefined ease-of-use by being the simplest 8-bit microcontrollers to program. Combined
More informationCPS-1848 PCB Design Application Note
Titl CPS-1848 PCB Design Application Note June 22, 2010 6024 Silver Creek Valley Road, San Jose, California 95138 Telephone: (408) 284-8200 Fax: (408) 284-3572 2010 About this Document This document is
More informationEMI. Chris Herrick. Applications Engineer
Fundamentals of EMI Chris Herrick Ansoft Applications Engineer Three Basic Elements of EMC Conduction Coupling process EMI source Emission Space & Field Conductive Capacitive Inductive Radiative Low, Middle
More information11 Myths of EMI/EMC ORBEL.COM. Exploring common misconceptions and clarifying them. MYTH #1: EMI/EMC is black magic.
11 Myths of EMI/EMC Exploring common misconceptions and clarifying them By Ed Nakauchi, Technical Consultant, Orbel Corporation What is a myth? A myth is defined as a popular belief or tradition that has
More informationMGA GHz 3 V, 17 dbm Amplifier. Data Sheet. Features. Description. Applications. Surface Mount Package. Simplified Schematic
MGA-853.1 GHz 3 V, 17 dbm Amplifier Data Sheet Description Avago s MGA-853 is an economical, easy-to-use GaAs MMIC amplifier that offers excellent power and low noise figure for applications from.1 to
More informationPCI-EXPRESS CLOCK SOURCE. Features
DATASHEET ICS557-01 Description The ICS557-01 is a clock chip designed for use in PCI-Express Cards as a clock source. It provides a pair of differential outputs at 100 MHz in a small 8-pin SOIC package.
More informationAdvanced Topics in EMC Design. Issue 1: The ground plane to split or not to split?
NEEDS 2006 workshop Advanced Topics in EMC Design Tim Williams Elmac Services C o n s u l t a n c y a n d t r a i n i n g i n e l e c t r o m a g n e t i c c o m p a t i b i l i t y e-mail timw@elmac.co.uk
More informationSurface Mount SOT-363 (SC-70) Package. Pin Connections and Package Marking GND 1 4 V CC
GHz Low Noise Silicon MMIC Amplifier Technical Data INA-63 Features Ultra-Miniature Package Internally Biased, Single 5 V Supply (12 ma) db Gain 3 db NF Unconditionally Stable Applications Amplifier for
More informationMK2705 AUDIO CLOCK SOURCE. Description. Features. Block Diagram DATASHEET
DATASHEET MK2705 Description The MK2705 provides synchronous clock generation for audio sampling clock rates derived from an MPEG stream, or can be used as a standalone clock source with a 27 MHz crystal.
More informationWhite paper. High speed and RF PCB routing : Best practises and recommandations
ALCIOM 5, Parvis Robert Schuman 92370 CHAVILLE - FRANCE Tel/Fax : 01 47 09 30 51 contact@alciom.com www.alciom.com Projet : White paper DOCUMENT : High speed and RF PCB routing : Best practises and recommandations
More informationDesign for EMI & ESD compliance DESIGN FOR EMI & ESD COMPLIANCE
DESIGN FOR EMI & ESD COMPLIANCE All of we know the causes & impacts of EMI & ESD on our boards & also on our final product. In this article, we will discuss some useful design procedures that can be followed
More informationLM V Monolithic Triple Channel 15 MHz CRT DTV Driver
220V Monolithic Triple Channel 15 MHz CRT DTV Driver General Description The is a triple channel high voltage CRT driver circuit designed for use in DTV applications. The IC contains three high input impedance,
More informationMGA GHz 3 V, 17 dbm Amplifier. Data Sheet
MGA-853.1 GHz 3 V, 17 dbm Amplifier Data Sheet Description Avago s MGA-853 is an economical, easy-to-use GaAs MMIC amplifier that offers excellent power and low noise figure for applications from.1 to
More informationLM2412 Monolithic Triple 2.8 ns CRT Driver
Monolithic Triple 2.8 ns CRT Driver General Description The is an integrated high voltage CRT driver circuit designed for use in high resolution color monitor applications. The IC contains three high input
More informationElectro-Magnetic Interference and Electro-Magnetic Compatibility (EMI/EMC)
INTROUCTION Manufacturers of electrical and electronic equipment regularly submit their products for EMI/EMC testing to ensure regulations on electromagnetic compatibility are met. Inevitably, some equipment
More informationLVDS Owner s Manual. A General Design Guide for National s Low Voltage Differential Signaling (LVDS) Products. Moving Info with LVDS
LVDS Owner s Manual A General Design Guide for National s Low Voltage Differential Signaling (LVDS) Products Moving Info with LVDS Revision 2.0 January 2000 LVDS Evaluation Boards Chapter 6 6.0.0 LVDS
More informationOCXO Layout Guidelines
OCXO Layout Guidelines Application Note: AN2093 2111 Comprehensive Drive Section 1: About this document. 1.1 Introduction The techniques included in this application note will help to ensure successful
More informationCMT2300AW Schematic and PCB Layout Design Guideline
AN141 CMT2300AW Schematic and PCB Layout Design Guideline Introduction This document is the CMT2300AW Application Development Guideline. It will explain how to design and use the CMT2300AW schematic and
More informationLow Noise Amplifiers for 2304, 3456, 5760, and MHz using the ATF PHEMT by Al Ward WB5LUA
Low Noise Amplifiers for 2304, 3456, 5760, and 10368 MHz using the by Al Ward INTRODUCTION The Hewlett-Packard device is described in a series of low noise amplifiers for 2304, 3456, 5760, and 10368 MHz.
More informationTN ADC design guidelines. Document information
Rev. 1 8 May 2014 Technical note Document information Info Content Keywords Abstract This technical note provides common best practices for board layout required when Analog circuits (which are sensitive
More informationHigh Voltage Charge Pumps Deliver Low EMI
High Voltage Charge Pumps Deliver Low EMI By Tony Armstrong Director of Product Marketing Power Products Linear Technology Corporation (tarmstrong@linear.com) Background Switching regulators are a popular
More informationMaxim Integrated Products 1
19-3533; Rev 0; 1/05 MAX9996 Evaluation Kit General Description The MAX9996 evaluation kit (EV kit) simplifies the evaluation of the MAX9996 UMTS, DCS, and PCS base-station downconversion mixer. It is
More informationLVDS Flow Through Evaluation Boards. LVDS47/48EVK Revision 1.0
LVDS Flow Through Evaluation Boards LVDS47/48EVK Revision 1.0 January 2000 6.0.0 LVDS Flow Through Evaluation Boards 6.1.0 The Flow Through LVDS Evaluation Board The Flow Through LVDS Evaluation Board
More informationData Sheet. MGA GHz 3 V, 14 dbm Amplifier. Description. Features. Applications. Simplified Schematic
MGA-8153.1 GHz 3 V, 1 dbm Amplifier Data Sheet Description Avago s MGA-8153 is an economical, easy-to-use GaAs MMIC amplifier that offers excellent power and low noise figure for applications from.1 to
More informationApplication Note 5525
Using the Wafer Scale Packaged Detector in 2 to 6 GHz Applications Application Note 5525 Introduction The is a broadband directional coupler with integrated temperature compensated detector designed for
More informationEL7302. Hardware Design Guide
Hardware Design Guide Version: Preliminary 0.0 Date: January. 2005 Approval: Etron technology, Inc P.O. Box 19-54 No.6 Technology Road V. Science-based Industrial Park, Hsinchu,30077 Taiwan, R.O.C. Tel:
More informationImproving the immunity of sensitive analogue electronics
Improving the immunity of sensitive analogue electronics T.P.Jarvis BSc CEng MIEE MIEEE, I.R.Marriott BEng, EMC Journal 1997 Introduction The art of good analogue electronics design has appeared to decline
More informationBest Design and Layout Practices for SiTime Oscillators
March 17, 2016 Best Design and Layout Practices 1 Introduction... 1 2 Decoupling... 1 3 Bypassing... 4 4 Power Supply Noise Reduction... 5 5 Power Supply Management... 6 6 Layout Recommendations for SiTime
More information1 of 11 30/08/2011 8:50 AM
1 of 11 30/08/2011 8:50 AM All Ferrite Beads Are Not Created Equal - Understanding the Importance of Ferrite Bead Material Behavior August 2010 Written by Chris Burket, TDK Corporation A common scenario:
More information1-Input/4-Output Video Distribution Amplifiers MAX4137/MAX4138
-00; Rev 0; / EVALUATION KIT AVAILABLE General Description The / are -input/-output voltagefeedback amplifiers that combine high speed with fast switching for video distribution applications. The is internally
More informationFreescale Semiconductor, I
Order this document by /D Noise Reduction Techniques for Microcontroller-Based Systems By Imad Kobeissi Introduction With today s advancements in semiconductor technology and the push toward faster microcontroller
More informationEMI Filters Demystified. By William R. Bill Limburg February 21, 2018 Phoenix Chapter, IEEE EMC Society
EMI Filters Demystified By William R. Bill Limburg February 21, 2018 Phoenix Chapter, IEEE EMC Society An EMI Filter Defined An EMI filter is a network designed to prevent unwanted electrical conducted
More informationSurface Mount SOT-363 (SC-70) Package. Pin Connections and Package Marking 4 V CC. Note: Package marking provides orientation and identification.
1.5 GHz Low Noise Silicon MMIC Amplifier Technical Data INA-52063 Features Ultra-Miniature Package Single 5 V Supply (30 ma) 22 db Gain 8 dbm P 1dB Unconditionally Stable Applications Amplifier for Cellular,
More informationApplication Note 5480
ALM-2712 Ultra Low-Noise GPS Amplifier with Pre- and Post-Filter Application Note 548 Introduction The ALM-2712 is a GPS front-end module which consists of a low noise amplifier with pre- and post-filters.
More information433MHz Single Chip RF Transmitter
433MHz Single Chip RF Transmitter nrf402 FEATURES True single chip FSK transmitter Few external components required On chip UHF synthesiser No set up or configuration 20kbit/s data rate 2 channels Very
More informationUnderstanding the Importance of Ferrite Bead Material Behavior
Magazine August 2010 All ferrite beads are not created equal Understanding the Importance of Ferrite Bead Material Behavior by Chris T. Burket, TDK Corporation A common scenario: A design engineer inserts
More informationICS PCI-EXPRESS CLOCK SOURCE. Description. Features. Block Diagram DATASHEET
DATASHEET ICS557-0 Description The ICS557-0 is a clock chip designed for use in PCI-Express Cards as a clock source. It provides a pair of differential outputs at 00 MHz in a small 8-pin SOIC package.
More informationDesigning for Electromagnetic Interference (EMI) Compliance
Designing for Electromagnetic Interference (EMI) Compliance Application Note by Tim Raper and Steve Knauber This application note describes how to integrate any microprocessor or microcontroller into an
More informationAnalogue circuit design for RF immunity
Analogue circuit design for RF immunity By EurIng Keith Armstrong, C.Eng, FIET, SMIEEE, www.cherryclough.com First published in The EMC Journal, Issue 84, September 2009, pp 28-32, www.theemcjournal.com
More informationUnderstanding, measuring, and reducing output noise in DC/DC switching regulators
Understanding, measuring, and reducing output noise in DC/DC switching regulators Practical tips for output noise reduction Katelyn Wiggenhorn, Applications Engineer, Buck Switching Regulators Robert Blattner,
More informationRB02. Hardware Reference Guide. Qualcomm Technologies, Inc. 80-YA Rev. A July 3, 2017
Qualcomm Technologies, Inc. RB02 Hardware Reference Guide 80-YA116-19 Rev. A July 3, 2017 Qualcomm is a trademark of Qualcomm Incorporated, registered in the United States and other countries. Other product
More informationCommon myths, fallacies and misconceptions in Electromagnetic Compatibility and their correction.
Common myths, fallacies and misconceptions in Electromagnetic Compatibility and their correction. D. A. Weston EMC Consulting Inc 15-3-2013 1) First topic an introduction These are some of the commonly
More informationSAW Filter PCB Layout
SAW Filter PCB Layout by Allan Coon Director, Filter Product Marketing Murata Electronics North America, c. 1999 troduction The performance of surface acoustic wave (SAW) filters depends on a number of
More informationApplication Note 58 Crystal Considerations with Dallas Real Time Clocks
Application Note 58 Crystal Considerations with Dallas Real Time Clocks Dallas Semiconductor offers a variety of real time clocks (RTCs). The majority of these are available either as integrated circuits
More informationFrequently Asked EMC Questions (and Answers)
Frequently Asked EMC Questions (and Answers) Elya B. Joffe President Elect IEEE EMC Society e-mail: eb.joffe@ieee.org December 2, 2006 1 I think I know what the problem is 2 Top 10 EMC Questions 10, 9
More informationCAD Layout Recommendations for the PowerBlox Family
Solved by APPLICATION NOTE ANP4 TM CAD Layout Recommendations for the PowerBlox Family Introduction The Sipex PowerBlox family of parts offers designers a very high power density solution for wide input
More informationEUA W Mono Filterless Class-D Audio Power Amplifier DESCRIPTION FEATURES APPLICATIONS. Typical Application Circuit
3-W Mono Filterless Class-D Audio Power Amplifier DESCRIPTION The EUA2011 is a high efficiency, 3W mono class-d audio power amplifier. A low noise, filterless PWM architecture eliminates the output filter,
More informationSurface Mount SOT-363 (SC-70) Package. Pin Connections and Package Marking GND. V dd. Note: Package marking provides orientation and identification.
GHz V Low Current GaAs MMIC LNA Technical Data MGA-876 Features Ultra-Miniature Package.6 db Min. Noise Figure at. GHz. db Gain at. GHz Single + V or V Supply,. ma Current Applications LNA or Gain Stage
More informationPI3HDMIxxx 4-Layer PCB Layout Guideline for HDMI Products
PI3HDMIxxx 4-Layer PCB Layout Guideline for HDMI Products Introduction The differential trace impedance of HDMI is specified at 100Ω±15% in Test ID 8-8 in HDMI Compliance Test Specification Rev.1.2a and
More information1 Introduction External Component Requirements AC Coupling Capacitors on high speed lanes... 2
PI3TB212 PI3TB212 Thunderbolt Application Information Table of Contents 1 Introduction... 2 2 External Component Requirements... 2 2.1 AC Coupling Capacitors on high speed lanes... 2 2.2 Pull-down Resistor
More informationHV739 ±100V 3.0A Ultrasound Pulser Demo Board
HV79 ±00V.0A Ultrasound Pulser Demo Board HV79DB Introduction The HV79 is a monolithic single channel, high-speed, high voltage, ultrasound transmitter pulser. This integrated, high performance circuit
More informationDesign Considerations for Highly Integrated 3D SiP for Mobile Applications
Design Considerations for Highly Integrated 3D SiP for Mobile Applications FDIP, CA October 26, 2008 Joungho Kim at KAIST joungho@ee.kaist.ac.kr http://tera.kaist.ac.kr Contents I. Market and future direction
More informationDecoupling capacitor placement
Decoupling capacitor placement Covered in this topic: Introduction Which locations need decoupling caps? IC decoupling Capacitor lumped model How to maximize the effectiveness of a decoupling cap Parallel
More informationLF to 4 GHz High Linearity Y-Mixer ADL5350
LF to GHz High Linearity Y-Mixer ADL535 FEATURES Broadband radio frequency (RF), intermediate frequency (IF), and local oscillator (LO) ports Conversion loss:. db Noise figure:.5 db High input IP3: 25
More informationApplication Report. Battery Management. Doug Williams... ABSTRACT
Application Report SLUA392 August 2006 bq20z70/90 Printed-Circuit Board Layout Guide Doug Williams... Battery Management ABSTRACT Attention to layout is critical to the success of any battery management
More informationEUA2011A. Low EMI, Ultra-Low Distortion, 2.5-W Mono Filterless Class-D Audio Power Amplifier DESCRIPTION FEATURES APPLICATIONS
Low EMI, Ultra-Low Distortion, 2.5-W Mono Filterless Class-D Audio Power Amplifier DESCRIPTION The EUA2011A is a high efficiency, 2.5W mono class-d audio power amplifier. A new developed filterless PWM
More informationMaster Op-Doc/Test Plan
Power Supply Master Op-Doc/Test Plan Define Engineering Specs Establish battery life Establish battery technology Establish battery size Establish number of batteries Establish weight of batteries Establish
More informationMaxim Integrated Products 1
19-0569; Rev 0; 5/06 MAX2041 Evaluation Kit General Description The MAX2041 evaluation kit (EV kit) simplifies the evaluation of the MAX2041 UMTS, DCS, and PCS base-station up/downconversion mixer. It
More informationPCB DESIGN AND ASSEMBLY FOR POWER SUPPLIES
PCB DESIGN AND ASSEMBLY FOR POWER SUPPLIES Power supplies come in large varieties, can have different topologies, and feature numerous safeguards. Design of printed circuit boards (PCBs) for powers supplies
More information10 Safety earthing/grounding does not help EMC at RF
1of 6 series Webinar #3 of 3, August 28, 2013 Grounding, Immunity, Overviews of Emissions and Immunity, and Crosstalk Contents of Webinar #3 Topics 1 through 9 were covered by the previous two webinars
More informationMK LOW PHASE NOISE T1/E1 CLOCK GENERATOR. Features. Description. Block Diagram DATASHEET. Pullable Crystal
DATASHEET LOW PHASE NOISE T1/E1 CLOCK ENERATOR MK1581-01 Description The MK1581-01 provides synchronization and timing control for T1 and E1 based network access or multitrunk telecommunication systems.
More informationRecommendations for PHY Layout
Recommendations for PHY Layout Ron Raybarman 1394 Applications Group Abstract This document makes recommendations for the layout of the PHY and Link layer devices in an IEEE 1394 environment. The optimal
More informationApplication Note Receivers MLX71120/21 With LNA1-SAW-LNA2 configuration
Designing with MLX71120 and MLX71121 receivers using a SAW filter between LNA1 and LNA2 Scope Many receiver applications, especially those for automotive keyless entry systems require good sensitivity
More informationLM2405 Monolithic Triple 7 ns CRT Driver
LM2405 Monolithic Triple 7 ns CRT Driver General Description The LM2405 is an integrated high voltage CRT driver circuit designed for use in color monitor applications The IC contains three high input
More informationG6ALU 20W FET PA Construction Information
G6ALU 20W FET PA Construction Information The requirement This amplifier was designed specifically to complement the Pic-A-Star transceiver developed by Peter Rhodes G3XJP. From the band pass filter an
More informationPF3000 layout guidelines
NXP Semiconductors Application Note Document Number: AN5094 Rev. 2.0, 7/2016 PF3000 layout guidelines 1 Introduction This document provides the best practices for the layout of the PF3000 device on printed
More informationMAX1002/MAX1003 Evaluation Kits
9-50; Rev 0; 6/97 MAX00/MAX00 Evaluation Kits General Description The MAX00/MAX00 evaluation kits (EV kits) simplify evaluation of the 60Msps MAX00 and 90Msps MAX00 dual, 6-bit analog-to-digital converters
More informationSingle chip 433MHz RF Transceiver
Single chip 433MHz RF Transceiver RF0433 FEATURES True single chip FSK transceiver On chip UHF synthesiser, 4MHz crystal reference 433MHz ISM band operation Few external components required Up to 10mW
More informationCMT2210A Schematic and PCB Layout Design Guideline
AN107 CMT2210A Schematic and PCB Layout Design Guideline 1. Introduction The purpose of this document is to provide the guidelines to design a low power consumption, low BOM and high sensitivity CMT2210A
More informationPART MAX4144ESD MAX4146ESD. Typical Application Circuit. R t IN- IN+ TWISTED-PAIR-TO-COAX CABLE CONVERTER
9-47; Rev ; 9/9 EVALUATION KIT AVAILABLE General Description The / differential line receivers offer unparalleled high-speed performance. Utilizing a threeop-amp instrumentation amplifier architecture,
More informationTECHNICAL REPORT: CVEL Parasitic Inductance Cancellation for Filtering to Chassis Ground Using Surface Mount Capacitors
TECHNICAL REPORT: CVEL-14-059 Parasitic Inductance Cancellation for Filtering to Chassis Ground Using Surface Mount Capacitors Andrew J. McDowell and Dr. Todd H. Hubing Clemson University April 30, 2014
More informationAnaren 0805 (B0809J50ATI) balun optimized for Texas Instruments CC1100/CC1101 Transceiver
(ANN-2005) Rev B Page 1 of 13 Anaren 0805 (B0809J50ATI) balun optimized for Texas Instruments CC1100/CC1101 Transceiver Trong N Duong RF Co-Op Nithya R Subramanian RF Engineer Introduction The tradeoff
More information