Application and Technical Information Thread Milling System (TMS) Minimum Bore Diameters for Thread Milling
|
|
- Donna Conley
- 5 years ago
- Views:
Transcription
1 Inserts Application and Technical Information Minimum Bore iameters for Thread Milling UN-ISO-BSW tpi Technical ata Accessories Vintage Cutters Widia Cutters Thread Milling Slotting ie and Mold End Mills Face Mills cutter workpiece material pitch mm cutter dia. (1) K035TM1RW050-STN K045TM1RW050-STN11N K049TM1RW037LT11S K061TM1RW06-STN16T K067TMRW075-STN K075TM1RW075-STN16T K079TM1RW075-STN16N K087TM1RW100-STN16L K10TMRW100-STN ,5 0,75 1,0 1,5 1,5,0,5 3,0 3,5 4,0 4,5 5,0 5,5 6,0 minimum bore diameter () (inches) K118TM1RW100-STN7N K146TM1RW15-STN7N K165TMRW15-STN Cutting ata Recommendation 1.38 (UN) (ISO) (BSW) cutting speed (sfm) feed rate per grade KC610M grade KC60M grade KC635M revolution carbon steels < 187 HB carbon steels 187 to 0 HB alloy steel HB alloy steel HB stainless steel, austenitic < 10 HB stainless steel, martensitic < 31 HB stainless steel, ferritic < 45 HB cast steel < 140 HB cast steel 0-30 HB titanium alloys high-temperature (nickel and iron base) high-temperature (cobalt base) cast iron malleable iron bronze/copper aluminum NOTES: All thread milling inserts are full profile or cresting type. Inserts are designed to mill full thread depth in one revolution or pass. When machining difficult materials, two passes may be desired. A 60% thread depth on the first pass, and a 40% thread depth on the second pass is recommended. Thread relief grooves in blind holes are not necessary. Applications in this area may be machined with special inserts and cutter bodies. Quoted on request. Thread milling large parts requires considerably less horsepower compared to other threading methods. Thread milling produces short chips compared to stringy chips of other threading methods. One holder is suitable for many different thread pitches. PV coated inserts provide maximum tool life for a wide variety of materials. M370
2 Understanding Thread Milling In order to perform a thread milling operation, a milling machine with three-axis control, capable of helical interpolation, is required. Helical interpolation is a CNC function producing tool movement along a helical path. This helical travel combines circular movement in one plane with a simultaneous linear motion in a plane perpendicular to the first. For example, the path from point A to point B (figure A) on the envelope of the cylinder combines a circular movement in the X and Y plane with a linear movement in the Z direction. On most CNC systems, this function can be executed in two different ways: G0: helical interpolation in a clockwise direction G03: helical interpolation in a counterclockwise direction The thread milling operation (figure B) consists of circular rotation of the tool about its own axis together with an orbiting motion along the bore or workpiece circumference. uring one such orbit, the tool will move vertically one pitch length. These movements, combined with the insert geometry, create the required thread form. Inserts Face Mills End Mills α - - P - helix angle external diameter pitch There are three acceptable ways of approaching the workpiece with the tool to initiate production of the thread: 1. along a tangential arc. radially 3. along a tangential straight line NOTE: Climb milling is preferred. ie and Mold figure A Tangential Approach (arc) figure B With this method, the tool enters and exits the workpiece smoothly. No marks are left on the workpiece and there is no vibration, even with harder materials. Although it requires slightly more complex programming than the radial approach method (see next page), this is the method recommended for machining the highest quality threads. 1 - : rapid approach - 3: tool entry along tangential arc, with simultaneous feed along Z-axis 3-4: helical movement during one full orbit (360 ) 4-5: tool exit along tangential arc, with continuing feed along the Z-axis 5-6: rapid return Slotting Thread Milling Widia Cutters Accessories Technical ata Vintage Cutters internal thread Tangential Approach (line) This method is very simple, and has all of the advantages of the tangential arc method. However, it is applicable only to external threads. external thread 1 - : radial entry with simultaneous feed along the Z-axis - 3: helical movement during one full orbit (360 ) 3-4: radial exit M371
3 Inserts Face Mills Application and Technical Information Radial Approach 1 - : radial entry - 3: helical movement during one full orbit (360 ) 3-4: radial exit This is the simplest method. There are two characteristics worth noting about the radial approach: a. A small vertical mark may be left at the entry (and exit) point. This is of no significance to the thread itself. b. When using this method with very hard materials, there may be a tendency for the tool to vibrate as it approaches the full cutting depth. NOTE: Radial feed during entry to the full profile depth should be only 1/3 of the subsequent circular feed! ie and Mold End Mills internal thread Preparing for the Thread Milling Operation external thread Slotting Thread Milling Widia Cutters Vintage Cutters Accessories Technical ata calculation of feed rates at the cutting edge calculation of program feed rate internal thread (F 1 x d 1 ) P f = F 1 - The first step is to calculate the tool feed rate at the cutting edge. F 1 = ipt x nt x rpm where: F 1 = tool feed rate at the cutting edge (in./min.) ipt = inch per tooth (feed rate) nt = number of effective inserts in cutter rpm = rotational speed (spindle rpm) On most CNC machines, the feed rate required for programming is at the centerline of the tool. When dealing with linear tool movement, the feed rate at the cutting edge and the centerline are identical. But, with where: P f = program feed rate (in./min.) = major diameter (external thread) = minor diameter (internal thread) d 1 = cutting diameter, over insert The rotational speed (rpm) is calculated by the following formula: rpm = where: sfm = cutting speed, surface feet per minute d 1 = cutter diameter, over insert π = circular tool movement this is not the case. The following equations define the relationship between feed rates at the cutting edge and at the tool centerline. external thread 1 x sfm π x d 1 (F 1 x d 1 ) P f = F 1 + M37
4 Step-by-Step Thread Milling Example thread: internal right hand 1 1 /4 x 16 UN B RH(1) material: AISI 4140 (300 HB) thread diameters: (minimum bore dia.) = 1.18 o (nominal dia.) = 1.5 inch thread length:.50 inch efine the Appropriate Cutter: For best thread quality, the cutter with the largest d 1 (cutter diameter) possible should be used. This cutter diameter can be found in the table on page M370, as a function of pitch and minimum bore diameter. The result for the above example is that any cutter diameter 1.0 inch or smaller can be utilized. A cutter with a smaller d 1 will perform the thread milling operation in less time. The smaller d 1 may result in less tool rigidity, so it should be used with caution on very tough materials. Find the appropriate normal-length shank cutter on page M368. Use the minimum bore diameter table above. Choosing Insert Size The insert IC is defined by the selected cutter (STN16). Use the appropriate insert table on pages M363-M366. Find the appropriate normal-length shank cutter diameter on page M368. pitch (tpi) pitch mm 1,0 1,5 1,5,0 cutter dia. d 1 minimum bore diameter figure B: cutter selected: K079TMIRW075STN16N outer dimensions: d 1 =.79, R t (radius of tool) = d 1 =.395 Slotting ie and Mold End Mills Face Mills Inserts b insert a internal thread inch number size inch pitch thread of IC (mm) (tpi) length teeth catalog number insert selected: STN16 16UN-I Cutting ata Recommendation workpiece material selected carbide grade: KC610M selected cutting speed: 500 sfm selected feed:.004 ipt KC610M grade external thread catalog number b inch number thread of length teeth cutting speed (sfm) feed rate per mini thread mill grade KC610M grade KC60M revolution STN10 carbon steels (< 187 HB) carbon steels (187 to 0 HB) alloy steel (00-50 HB) alloy steel (50-35 HB) stainless steel austenitic (< 10 HB) grade cutter type 3 STN16 3UN-I STN16 3UN-E STN16 8UN-I STN16 8UN-E STN16 7UN-I STN16 7UN-E /8 4 STN16 4UN-I STN16 4UN-E STN16 0UN-I STN16 0UN-E (16) 18 STN16 18UN-I STN16 18UN-E STN16 16 STN16 16UN-I.56 9 STN16 16UN-E STN16 14UN-I.57 8 STN16 14UN-E STN16 13UN-I.54 7 STN16 13UN-E STN16 1UN-I.58 7 STN16 1UN-E.58 7 stock standard non-stock standard Choose the carbide grade, define the cutting speed and select the proper feed. KC60M Technical ata Accessories Vintage Cutters Widia Cutters Thread Milling KC610M KC60M M373
5 Step-by-Step Thread Milling Example (cont d.) Technical ata Accessories Vintage Cutters Widia Cutters Thread Milling Slotting ie and Mold End Mills Face Mills Inserts Calculate the feed rates: First, find the rpm. 1 x sfm 1 x 500 rpm = = = 418 rpm π x d x.79 Next, calculate the feed rate at the insert cutting edge (F 1 ): (using the chosen feed per tooth of.004.) F 1 = ipt x nt x rpm =.004 x 1 x 418 = 9.67 in./min. Finally, calculate the feed rate at the cutter centerline (F ): F 1 x ( d 1 ) 9.67 x ( ) F = = = 3.07 in./min Select the thread milling method. [Selected method...climb milling (preferred), refer to page 71.] Calculate the radius of the tangential arc R e : (R i C L ) + R o (.591.0) +.65 R e = = R o x.65 R e = in. Calculate the angle (β): R o R e β = 90 + arc sin ( ) R e β = 90 + arc sin ( ) β = = = 95 10' Calculate the movement along the Z-axis during the entry approach from point A to point B (Zα). (NOTE: P = pitch) α.065 Zα = P(in.) x = x =.0156 in., since α = Calculate the X and Y values at the start of the entry approach. X = 0 Y = R i + C L = =.571 in. efine Z-axis location at the start of the entry approach. (NOTE: L = length of thread) Z = (L + Zα) = ( ) =.5156 in. efine the starting point. X a = 0 Y a = 0 CNC Program (Fanuc 11M) % N10G90G00G57X0.000Y0.000 N0G43H10Z0.M3S417 N30G91G00X0.Y0.Z N40G4160X0.000Y Z0. N50G03X0.650Y0.5710Z0.0156R0.5733F3.06 N60G03X0.Y0.Z0.065I 0.65J0. N70G03X 0.65Y0.5710Z0.0156R N80G00G40X0.Y Z0. N90G49G57G00Z8.0M5 N100M30 R i = % = minor diameter R o o = o = nominal diameter α = 90 M374
6 Appendix A erivation of Formulas for Internal Thread Milling Appendix B erivation of Formulas for External Thread Milling Inserts R e, β, and X can be found by a geometric analysis of the entry path. This entry path is defined by the tool traveling along a circular path, with a radius of R e about the point C. (R i C L ) + R o derivation of R e = R o Triangle OAC enables us to simply solve for R e. Note that OAC is a right angle triangle, and that: OA = R i C L CA = R e OC = R o R e Pythagoras law states: OA + OC = AC Replacing actual values, we get: (R i C L ) + (R o R e ) = R e Simplifying, we get: R e = (R i C L ) + R o R o R e, β, and X can be found by a geometric analysis of the entry path. This entry path is defined by the tool traveling along a circular path, with a radius of R e about the point C. (R o + C L ) + R i derivation of R e = R i Triangle OAC enables us to simply solve for R e. Note that OAC is a right angle triangle, and that: OA = R o + C L CA = R e OC = R e R i Pythagoras law states: OA + OC = AC Replacing actual values, we get: (R o + C L) + (R e R i) = R e Simplifying, we get: (R o + C L ) +R i R e = R i Thread Milling Slotting ie and Mold End Mills Face Mills Find the angle β. β = 90 + σ OC (R o R e ) sin σ = = CA R e Technical ata Accessories Vintage Cutters Widia Cutters R o R e σ = arc sin ( ) R e R o R e Therefore, β = 90 + arc sin ( ) R e Find the angle β. β can be easily found using the same triangle: AO (R o + C L ) sin β = = AC R e R o + C L β = arc sin ( ) R e M375
7 Inserts Application and Technical Information Thread Milling Troubleshooting problem possible cause solution Technical ata Accessories Vintage Cutters Widia Cutters Thread Milling Slotting ie and Mold End Mills Face Mills cutting speed too high Reduce cutting speed. excessive insert flank wear chip is too thin Increase feed rate. Insert Tolerance Classes insufficient coolant Increase coolant quantity/pressure. Reduce feed rate. chipping of chip is too thick Use the tangential arc method of entrance. cutting edge Increase rpm. vibration Check rigidity. material cutting speed too slow Increase cutting speed. build-up on the chip thickness too small Increase feed rate. cutting edge chatter / vibration feed rate is too high Reduce the feed. profile is too deep (coarse pitch threads) thread length is too long insufficient thread accuracy tool deflection Execute two passes, each with increased cutting depth. Execute two passes, each cutting only half the thread length. Execute two passes, each cutting only half of the thread length. Reduce feed rate. Execute a zero cut. thread designation standard designation tolerance class UN ANSI B A/B *UNJ MIL-S-8879A 3A/3B ISO R6 (IN 13) 6g/6H NPT USAS B.1 : 1968 standard NPT NPTF ANSI B standard BSW B.S. 84 : 1956, IN 59, ISO 8/1 : 198 medium class A BSPT B.S. 1 : 1985 standard BSPT *ACME ANSI B1/5 : G *PG IN standard *TR IN 103 7e/7H *NOTE: enotes thread forms quoted on request as non-stock standards (4-6 weeks delivery). M376
8 The following are a few thread milling methods (work directions). NOTE: Climb milling results in lower cutting forces, better chip development, higher thread surface quality and longer insert life. Therefore, it should be used whenever possible. But, in the case of some hardened materials or when milling certain difficult-to-machine exotic materials, conventional milling may be preferred. Methods of External Thread Milling Inserts Face Mills ie and Mold Widia Cutters Vintage Cutters Technical ata Accessories Thread Milling Slotting End Mills right-hand thread... conventional milling right-hand thread... climb milling left-hand thread... conventional milling Methods of Internal Thread Milling left-hand thread... climb milling right-hand thread... conventional milling right-hand thread... climb milling left-hand thread... conventional milling left-hand thread... climb milling M377
UN THREAD MILLS SINGLE PROFILE (SPTM) - SOLID CARBIDE. Scientific Cutting Tools, Inc. OAL 60º THREAD MILLS
UN SINGLE PROFILE (SPTM) - SOLID CARBIDE UN Q A B 60º C S Fine and coarse threads ranging from #00 to 1¼ + can be milled using the 19 varieties of these single profile thread mills. SPECIALTY PORT - CAVITY
More informationSTUB ACME - INTERNAL AND EXTERNAL
STUB ACME - INTERNAL AND EXTERNAL SOLID CARBIDE SINGLE PROFILE ACME Q A 29º B C S Solid carbide for maximum tool rigidity coating for increased performance Single start threads only SPECIALTY PORT - CAVITY
More informationThread Mills.
Tool Selection Internal Threads......................................................S2 Tool Selection UN Internal Threads.......................................................S3 Indexable End Mills Weldon
More informationMETRIC THREAD MILLS SINGLE PROFILE (SPTM) - SOLID CARBIDE. Scientific Cutting Tools, Inc. Q A C OAL 60º THREAD MILLS METRIC
METRIC SINGLE PROFILE (SPTM) - SOLID CARBIDE METRIC Q A B 60º C S With just 19 varieties of Thread Mills, fine and coarse threads ranging from M1.2 to M30+ can be milled SPECIALTY PORT - CAVITY INDEXABLE
More informationSolid Carbide Thread Milling Cutters
Solid Carbide Thread Milling Cutters Second Edition Thread milling cutters by Features and Benefits: Sub-micro grain carbide substrate Longer tool life with tighter tolerances More cost-effective than
More informationThread Mills. Solid Carbide Thread Milling Cutters
Thread Mills Solid Carbide Thread Milling Cutters Thread milling cutters by Features and Benefits: Sub-micro grain carbide substrate Longer tool life with tighter tolerances More cost-effective than indexable
More informationOptimized flute design Better chip evacuation. Carbide substrate Higher heat resistance, higher speed.
Thread Mills Available for the first time, our solid thread mills are designed to be the highest quality thread milling solution. WIDIA-GTD Cut up to 63 HRC. Improved overall thread quality. Optimized
More informationTHE PROBLEM OF TOOL SELECTION FOR MILLING LARGE INTERNAL THREADS
THE PROBLEM OF TOOL SELECTION FOR MILLING LARGE INTERNAL THREADS Mladen Bošnjaković Dragomir Moškun Marko Jerković M.Sc. Mladen Bošnjaković, Slavonski Brod University of Applied Science, Dr. M. Budaka
More informationHIGH PERFORMANCE CARBIDE THREAD MILLS
HIGH PERFORMANCE CARBIDE THREAD MILLS TM Series HIGH PERFORMANCE CARBIDE THREAD MILLS table of contents Introduction... page 1 Understanding Milling... page 2 Niagara Mill Advantages... page 3 High Performance
More informationTHREAD MILLING. A Quick Reference Pocket Guide. Overall Length. Length of Cut. Cutter Diameter.
THREAD MILLING A Quick Reference Pocket Guide Overall Length Length of Cut Shank Diameter Cutter Diameter www.alliedmachine.com Whatever type of holemaking you do, Allied is here help. Whether you re a
More informationMetal Cutting - 5. Content. Milling Characteristics. Parts made by milling Example of Part Produced on a CNC Milling Machine 7.
Content Metal Cutting - 5 Assoc Prof Zainal Abidin Ahmad Dept. of Manufacturing & Industrial Engineering Faculty of Mechanical Engineering Universiti Teknologi Malaysia 7. MILLING Introduction Horizontal
More informationSINGLE POINT TOOLS. Mini Boring Bars Mini Boring Bars come in a range of diameters from to inch. They are fluted for maximum strength.
SINGLE POINT TOOLS All single point tools are designed for internal machining on a lathe. The helical boring bars can be used for both lathe and mill applications. All cutting tools are made from premium
More informationCARBIDE END MILLS SPECIFICATIONS
SPECIFICATIONS COATING GUIDE Material Hardness TiN TiCN TiALN Austentic Stainless Steel < 35 HRc * X Martinistic Stainless Steel < 35 HRc * X Martinistic Stainless Steel >= 35 HRc X PH Stainless Steel
More information2018 PRICE LIST SOLID CARBIDE THREAD MILLS
2018 PRICE LIST SOLID CARBIDE THREAD MILLS NORTH AMERICAN TOOL HISTORY & OVERVIEW North American Tool was founded in 1986, by the father and son team of Kenyon Y. Taylor and Roger K. Taylor. Working in
More informationCHAPTER 23 Machining Processes Used to Produce Various Shapes Kalpakjian Schmid Manufacturing Engineering and Technology 2001 Prentice-Hall Page 23-1
CHAPTER 23 Machining Processes Used to Produce Various Shapes Manufacturing Engineering and Technology 2001 Prentice-Hall Page 23-1 Examples of Parts Produced Using the Machining Processes in the Chapter
More informationTRAINING MANUAL. Part INTRODUCTION TO TWIST DRILLS
PRESTO INTERNATIONAL UK LTD TRAINING MANUAL Part 2 INTRODUCTION TO TWIST DRILLS - 1 - DEFINITION:- A rotary end cutting tool having two or more cutting lips, and having two or more spiral (helical) or
More informationLecture 15. Chapter 23 Machining Processes Used to Produce Round Shapes. Turning
Lecture 15 Chapter 23 Machining Processes Used to Produce Round Shapes Turning Turning part is rotating while it is being machined Typically performed on a lathe Turning produces straight, conical, curved,
More informationTypical Parts Made with These Processes
Turning Typical Parts Made with These Processes Machine Components Engine Blocks and Heads Parts with Complex Shapes Parts with Close Tolerances Externally and Internally Threaded Parts Products and Parts
More informationINNOVATIONS CATALOG Indexable Thread Milling
www.kennametal.com INNOVATIONS CATALOG Indexable Thread Milling NEW Indexable Thread Milling Products The latest Kennametal Indexable Thread Milling tools deliver longer tool life and higher productivity
More informationBSF. Large Ratio Automatic Back Counterboring & Spotfacing Tool
BSF Large Ratio Automatic Back Counterboring & Spotfacing Tool Counterbores up to 2.3xd Replaceable carbide coated blades for extended life Very simple to use Suitable for CNC machines with through coolant
More informationChapter 24 Machining Processes Used to Produce Various Shapes.
Chapter 24 Machining Processes Used to Produce Various Shapes. 24.1 Introduction In addition to parts with various external or internal round profiles, machining operations can produce many other parts
More information11/15/2009. There are three factors that make up the cutting conditions: cutting speed depth of cut feed rate
s Geometry & Milling Processes There are three factors that make up the cutting conditions: cutting speed depth of cut feed rate All three of these will be discussed in later lessons What is a cutting
More informationINDEX. List Price Catalog - Current Pricing On Our Website. List Price Catalog - Check Website For Current Pricing. * = additional sizes added
INDEX List Price Catalog - Check Website For Current Pricing * = additional sizes added PG CATEGORY NOTE 4 Threadmill - UNC/UNF * 5 Threadmill - UNC/UNF (Continued) & Thread Pac 6 Threadmill - NPT/NPTF
More informationPitch Perfect Threading. Pitch Perfect Threading
Pitch Perfect Threading 1 2 Pitch Perfect Threading 3 Process considerations Threading methods Existing Is the process stable today Is the productivity maximized Is chip control acceptable Is the quality
More informationFMA 2000 / 5 FMA 63 / 5 FM 1000 / FM 25 / Copy Milling Program Tool Contents. Milling Cutters Identification System Arbor
Copy Milling Program Tool Contents FM Style 1 Toroid Cylindrical End Milling Cutter 42/43 FM Style 2 Toroid Taper End Milling Cutter 42/43 FMA Arbor Style Milling Cutter 42/43 Insert ata 44/45 Cutting
More informationPCD Cartridge Style Face Mill and End Mill Program
PC Cartridge Style Face Mill and End Mill Program soft, free- non-ferrous metals (eg: 6061 aluminum, brass, and copper) graphite, carbon, green ceramics, fiber-reinforced plastics, and fiberboard low-silicon
More informationINDEXABLE BORING BAR AND INSERTS FLAT TOP, CHIP CONTROL, CBN, AND PCD
INDEXABLE BORING BAR AND S FLAT TOP, CHIP CONTROL,, AND 80 Diamond.156 IC R.156.040 80 DIAMOND FLAT TOP 80 DIAMOND CHIP CONTROL AT6+ 0.003 ACD5031 ACD5031E AT6+ 0.007 ACD5071 ACD5071E AT6+ 0.015 ACD5151
More informationFMA 2000 / 5 FMA 63 / 5 FM 1000 / FM 25 / Copy Milling Program Tool Contents. Milling Cutters Identification System Arbor
Copy Milling Program Tool Contents FM Style 1 Toroid Cylindrical End Milling Cutter 38/39 FM Style 2 Toroid Taper End Milling Cutter 38/39 FMA Arbor Style Milling Cutter 38/39 Insert ata 40/41 Cutting
More informationLEADING SOLUTIONS IN THREAD MILLING TECHNOLOGY
LEADING SOLUTIONS IN THREAD MILLING TECHNOLOGY Thread with Maximum Confidence, Depth, Versatility and Economy. Emuge Shur-Thread TM, Threads-All TM, Vario-Z and NPT Solid Carbide Thread Mills; and Gigant-ic
More information18mm Insert Face Mill
January 2005 / NEW-033 PAGE 1 OF 9 18mm Insert Face Mill MATERIAL Cast Iron, Stainless Steel, Carbon Steel, Hi-Temp Alloys, Titanium, Inconel DIAMETER RANGE 3.00" - 12.00" LEAD ANGLES 0º and 45º INSERT
More informationCopy Milling Program Tools
Millstar face mills are equally useful on newer high velocity machines and older slower equipment and will optimize milling performance of all your machine tools. The hardened tool bodies can be run at
More informationMachining Processes Used to Produce Various Shapes. Dr. Mohammad Abuhaiba
Machining Processes Used to Produce Various Shapes 1 Homework Assignment Due Wensday 28/4/2010 1. Show that the distance lc in slab milling is approximately equal to for situations where D>>d. (see Figure
More informationThe Engineer s Guide to Identifying Lead Screw Thread Forms
The Engineer s Guide to Identifying Lead Screw Thread Forms Thread Forms There are hundreds of different thread forms that have been designed over several decades. There are only a few specific thread
More informationUFO Family P.10 P.46 P.50. UFO Family Common Tool Holder P. 2. UFO T-slot Cutter. UFO Thread Milling Cutter P.21
UFO Family UFO design is Y.T. s patented design for accurate centering and minimized eccentricity. It is named after UFO space ship because of its insert design. The holders of the entire series can fit
More informationTHREAD MILLS - NPT - STRAIGHT FLUTE
THRED MILL NPT PECILTY PORT - CVITY INDEXLE INGLE POINT THRED MILL - NPT - TRIGHT FLUTE OLID CRIDE (NTIONL PIPE TPER) THRED / PITCH THRED / PITCH TRIGHT FLUTE - NPT UNCOTED LTiN+ 1/16, 1/8-27 0.218 0.534
More informationROOP LAL Unit-6 (Milling) Mechanical Engineering Department
Notes: Milling Basic Mechanical Engineering (Part B, Unit - I) 1 Introduction: Milling is a machining process which is performed with a rotary cutter with several cutting edges arranged on the periphery
More informationComputer Numeric Control
Computer Numeric Control TA202A 2017-18(2 nd ) Semester Prof. J. Ramkumar Department of Mechanical Engineering IIT Kanpur Computer Numeric Control A system in which actions are controlled by the direct
More informationPARTING ISCAR PARTING USER GUIDE. Parting and Grooving. Insert Positioning
90 80 0 70 10 60 20 50 30 40 Parting and Grooving Selection of Inserts For a proper match of insert and cutting material to application, the following variables must be taken into consideration: Width
More informationAPOLLO. Variable Helix Corner Radius End Mills. Excellent for Alloy Steel, Nickel Inconel Alloys, Stainless and Carbon Steel
Variable Helix Corner Radius End Mills Excellent for Alloy Steel, Nickel Inconel Alloys, Stainless and Carbon Steel Unequal Flute Design for Chatter Resistance Great for Roughing or Finishing High Performance
More informationEnd Mills 4. Cutting Tools 1 (Cont d) End-mills (Cont d)
Outline Review of Milling Cutting Tools Milling Milling Operations Workpiece Materials Tool Selection Machining Tips Toolholders Fixtures Cutting Tools HSS tools Coated (TiN, Al O 3, TiAlN,...) versions
More informationTechnical Information. Manchester...H1-H17 OTM...H18-H30. lower cost per cut.
Technical Information Manchester...H1-H17 OTM...H18-H30 MANCHESTER TOOLS lower cost per cut CUTTING www.manchestertools.com OTM TECH SUPPORT The technical section of this catalog is intended to provide
More informationChapter 23 Drilling and Hole Making Processes. Materials Processing. Hole Making Processes. MET Manufacturing Processes
MET 33800 Manufacturing Processes Chapter 23 Drilling and Hole Making Processes Before you begin: Turn on the sound on your computer. There is audio to accompany this presentation. Materials Processing
More informationQuick Change Carbide & Steel Boring Bar Instructions Manual
Workpiece Rigidity 1 Work holding Use the proper chuck and jaws to hold the work-piece, to assure that the part is held with maximum rigidity and stability under cutting force. 2 Steady Rest Support When
More informationTHREAD CUTTING & FORMING
THREAD CUTTING & FORMING Threading, Thread Cutting and Thread Rolling: Machining Threads on External Diameters (shafts) Tapping: Machining Threads on Internal Diameters (holes) Size: Watch to 10 shafts
More informationWhat Does A CNC Machining Center Do?
Lesson 2 What Does A CNC Machining Center Do? A CNC machining center is the most popular type of metal cutting CNC machine because it is designed to perform some of the most common types of machining operations.
More informationCat.3a Super Power Drill Super Drill
www.jic-tools.com.tw Cat.3a Super Power Drill Super Drill WE HAVE INVESTED RESOURCES IN THE DESIGN & MANUFACTURE OF INSERTED CUTTERS Cost Saving Our innovative tooling design upgrades productivity and
More informationJet-Stream Modular Carbide & Steel Boring Bar Instructions Manual
Workpiece Rigidity 1 Work holding Use the proper chuck and jaws to hold the work-piece, to assure that the part is held with maximum rigidity and stability under cutting force. 2 Steady Rest Support When
More informationBULLDOG CUTTING TOOLS PROUDLY MADE IN THE USA THREAD MILLING
BULLDOG CUTTING TOOLS THREAD MILLING 126 Jackson St. Red Bud, IL 62278 Toll Free Phone: 1 (844) 441-5624 Fax: (618) 282-2831 sales@bulldogcut.com PROUDLY MADE IN THE USA SAFETY PRECAUTIONS Cutting tools
More informationKennametal Twist Drills KHSS Drill Dictionary
Kennametal Twist KHSS Drill Dictionary shank diameter tang tang drive axis taper shank shank length neck straight shank point angle helix angle flutes flute length body overall length drill diameter lip
More informationTrade of Toolmaking. Module 6: Introduction to CNC Unit 2: Part Programming Phase 2. Published by. Trade of Toolmaking Phase 2 Module 6 Unit 2
Trade of Toolmaking Module 6: Introduction to CNC Unit 2: Part Programming Phase 2 Published by SOLAS 2014 Unit 2 1 Table of Contents Document Release History... 3 Unit Objective... 4 Introduction... 4
More informationCUTTING TOOLS FROM SANDVIK COROMANT. Small part machining TURNING PARTING AND GROOVING THREADING MILLING DRILLING
CUTTING TOOLS FROM SANDVIK COROMANT Small part machining TURNING PARTING AND GROOVING THREADING MILLING DRILLING Table of contents Introduction 2 Sliding head machines 4 Ordering information 55 Application
More informationChapter 22 MACHINING OPERATIONS AND MACHINE TOOLS
Chapter 22 MACHINING OPERATIONS AND MACHINE TOOLS Turning and Related Operations Drilling and Related Operations Milling Machining Centers and Turning Centers Other Machining Operations High Speed Machining
More informationLesson 2 Understanding Turning Center Speeds and Feeds
Lesson 2 Understanding Turning Center Speeds and Feeds Speed and feed selection is one of the most important basic-machining-practice-skills a programmer must possess. Poor selection of spindle speed and
More informationUNIT 9b: SCREW FASTENERS Introduction Functions Screw Features Elements Terms of a Thread Profile
UNIT 9b: SCREW FASTENERS Introduction A mechanical screw is a cylinder or cone that has a helical ridge called a thread. A helix has one or more turns, so a screw can have several turns. If the helix is
More informationDesign Guide: CNC Machining VERSION 3.4
Design Guide: CNC Machining VERSION 3.4 CNC GUIDE V3.4 Table of Contents Overview...3 Tolerances...4 General Tolerances...4 Part Tolerances...5 Size Limitations...6 Milling...6 Lathe...6 Material Selection...7
More informationChapter 24. Machining Processes Used to Produce Various Shapes: Milling
Chapter 24 Machining Processes Used to Produce Various Shapes: Milling Parts Made with Machining Processes of Chapter 24 Figure 24.1 Typical parts and shapes that can be produced with the machining processes
More informationMACHINING PROCESSES: TURNING AND HOLE MAKING. Dr. Mohammad Abuhaiba 1
MACHINING PROCESSES: TURNING AND HOLE MAKING Dr. Mohammad Abuhaiba 1 HoweWork Assignment Due Wensday 7/7/2010 1. Estimate the machining time required to rough cut a 0.5 m long annealed copper alloy round
More informationExternal Turning. Outline Review of Turning. Cutters for Turning Centers
Outline Review of Turning External Turning 3 External Turning Parameters Cutting Tools Inserts Toolholders Machining Operations Roughing Finishing General Recommendations Turning Calculations Machining
More informationSLIDE SHAFT PRODUCTS. 777 Schwab Road, Suite T, Hatfield, PA Toll Free: Fax:
SLIDE SHAFT PRODUCTS Materials Materials of NB slide shafts are selected AISI 52100, 1060, and 0C (or equivalent) on the basis of hardenability, fatigue strength, wear resistance, and toughness. AISI
More informationTHREAD MILLS - METRIC
METRIC Q - METRIC TRIGHT FLUTE - CRIDE FULL PROFILE hort length-of-cut for ideal length-to-diameter ratio Polished flute face for optimum performance Made with premium submicron grade carbide Internal
More informationEngraving with a Rigid Tool Engraving Tool Feeds and Speeds
Engraving with a Rigid Tool Engraving Tool Feeds and Speeds Material 3000 RPM 6000 RPM 7500 RPM 10000 RPM Aluminum/Aluminum Alloys 6 12 15 20 Brass/Bronze 6 12 15 20 Copper/Copper Alloys 6 12 15 20 Cast
More informationCUTTING TOOLS FROM SANDVIK COROMANT. Small part machining TURNING PARTING AND GROOVING THREADING MILLING DRILLING
CUTTING TOOLS FROM SANDVIK COROMANT Small part machining TURNING PARTING AND GROOVING THREADING MILLING DRILLING Table of contents Introduction 2 Sliding head machines 4 Ordering information 55 Application
More informationThe Selection of Manufacturing Engineering Process; By Dr. Saied. M. Darwish
CONTENTS MILLING OPERATIONS CONTENTS 6.1 Milling operation Milling is a machining operation in which a workpiece is fed past a rotating cylindrical tool with multiple cutting edges. This cutting tool in
More informationUN THREAD MILLS STRAIGHT FLUTE - SOLID CARBIDE FULL PROFILE SHANK DIA.
MILL Q MILL TRIGHT FLUTE - OLID CRIDE FULL PROFILE Optional short length-of-cut for ideal length-to-diameter ratio Cuts C, F, EF,, and J (internal only) Internal crest cutting design provides strongest
More informationNPA. Expansion of the HM390 Triangular Inserts Line with Tools Carrying 5 mm Edged Inserts. New Product Announcement. Page 1 / 9
NPA Expansion of the HM390 Triangular Inserts Line with Tools Carrying 5 mm Edged Inserts Page 1 / 9 Page 2 / 9 Highlights Tools carrying triangular inserts with 5 mm helical cutting edges Effective and
More informationA Review on Optimization of Process Parameters for Material Removal Rate and Surface Roughness for SS 202 Material During Face Milling Operation
IJIRST International Journal for Innovative Research in Science & Technology Volume 1 Issue 11 April 2015 ISSN (online): 2349-6010 A Review on Optimization of Process Parameters for Material Removal Rate
More informationUp to 5 3 from 5 to 10 4 from 10 to 18 6 from 18 to 35 8
Reamers They are the most used tools for the finishing holes. Can be divided into various categories, such as hand-reamers and those used in machine tools, reamers in highspeed steel, in carbide; inserted
More informationProduct Information Report Maximizing Drill Bit Performance
Overview Drills perform three functions when making a hole: Forming the chip The drill point digs into the material and pushes up a piece of it. Cutting the chip The cutting lips take the formed chip away
More informationSpeed (SFM) Radial DOC x D. .5 x D. 1 x D. .5 x D. 1 x D. .5 x D.
GP High Performance 4 Flute End Mills TyCarb GP High Performance end mills feature Differential flute spacing to achieve virtually chatter free machining in a wide range of materials. Excellent results
More informationMission Statement. 2005, Manchester Tool Company. All rights reserved.
Mission Statement Manchester Tool Company shall provide tooling systems to the metal cutting and similar industries, specializing in cutoff, grooving and complimentary niche products. We are dedicated
More informationUPDATE. NEW Gold-QuadF 09 09mm IC Insert Sizes
Styles: End Mill 15G1F Face Mill 5G5F, 5G6F s: 1.000" - 3.000" Inserts: SDXS0904MPR-MM SDXS0904MPR-MR SDXS0904MPR-MR1 Grades: IN4004 IN4005 IN4030 IN4035 UPDATE NEW Gold-QuadF 09 09mm IC Insert Sizes Features
More informationT360. Holders and Inserts - T-Cap. Features T333. Holders T335. Inserts T336. Clamping units T337. Sleeves for clamping units T338.
T358 T329 Holders and Inserts - T-Cap Features Holders Inserts Clamping units Sleeves for clamping units T-CAP Kits T333 T335 T336 T337 T338 T339 User Guide Comparison test results Surface finish Tool
More informationMMT series. MMT series for precise and efficient threading. New Threading Tools
New ing Tools 2005.6. Update B053G Expanded Insert MMT series MMT series for precise and efficient threading Series expanded, additional M-class inserts with 3-D chip breakers Tough new grade, VP15TF for
More informationTaps. Taps - Technical Info. Torque Cut High Performance HSSE Ring Colored Taps Technical Information. - Technical Information
Torque Cut High Performance HSSE Ring Colored Taps Technical Information RedLine Torque Cut High Performance Taps give you greater performance when tapping Steel Alloys, Stainless Steels, Titanium and
More informationChapter 23: Machining Processes: Turning and Hole Making
Manufacturing Engineering Technology in SI Units, 6 th Edition Chapter 23: Machining Processes: Turning and Hole Making Chapter Outline 1. Introduction 2. The Turning Process 3. Lathes and Lathe Operations
More informationFigure N 1- Characteristic angles of a drill
Basic of drill In these technical descriptions for simplicity we use the term drill instead of the more complete name twist drill bits. The drill is the tool universally used to make holes in any material.
More informationCOFA. Deburring Tool for Elliptical or Contoured Surfaces. increased performance. from stock
Deburring Tool for Elliptical or Contoured Surfaces increased performance from stock Cat. No. HTC015 Introduction Catalog HTC015No. HTC14 The HEULE COFA deburring tool removes burrs from the front and
More informationMachining Strenx and Hardox. Drilling, countersinking, tapping, turning and milling
Machining and Drilling, countersinking, tapping, turning and milling and are registered trademarks. These steel grades are manufactured only by SSAB. high strength steel and wear plate are steel grades
More informationUPDATED. PCD & CBN Tangential Milling. Features:
Diameters Metric: 5.0 mm 50 mm Inch:.0 0.0 Bodies Cylindrical Shell Type Integral on request UPDATED PCD & CBN Tangential Milling TEDIFEED is the newest line of mill with tangential inserts available with
More informationNC Spot Drill with Patented indexable carbide insert.
with Patented indexable carbide insert. High Efficiency! Low Cost! CNC Lathes, CNC Turning Centers and Machining Centers. One tool will perform multiple applications. Long tool life. Each insert has four
More informationThreading insert. Six series. New product for turning
New product for ISO metric thread Six series pitch thread Whitworth thread Unified thread British standard pipe thread American standard pipe thread Fully ground high precision inserts for high quality,
More informationThink efficiency, Think HSS MILLING
Think efficiency, Think HSS MILLING SUMMARY MILLING TOOLS 2 Zoom on a milling cutter 3 Which HSS for maximum efficiency? 4 Coatings for the best performance 5 Vocabulary 6 Choose the right design 7 Select
More informationPREVIEW COPY. Table of Contents. Using the Horizontal Milling Machine...3. Lesson Two Slab Milling Procedures...19
Table of Contents Lesson One Using the Horizontal Milling Machine...3 Lesson Two Slab Milling Procedures...19 Lesson Three Milling Slots and Angles...35 Lesson Four Straddle, Side, and Face Milling...51
More informationBASIC TECHNICAL INFORMATION FOR REAMERS FLUTE STYLES
BASIC TECHNICAL INFORMATION FOR HANNIBAL CARBIDE would like to inform you of some basic technical knowledge regarding reamers. Following these guidelines will reduce overall set-up time, while increasing
More informationLower Spindle Power Consumptionn
ower Spindle Power Consumptionn > Five cutters for drilling Ø13~Ø50 mm. > One insert for all kind of materials. > The drilling is done by helical interpolation. (circular ramping milling) Nine9 NC Helix
More informationTAP & DIE PRICE LIST INDEX
TAP & DIE PRICE LIST INDEX ANPT Die Page 4 BA Die Page 4 BA Tap Page 17 BSF Tap Page 19 BSB Die Page 4 BSB Tap Page 17 BSCY Tap Page 17 BSF Die Page 3 BSP Die Page 4 BSP Tap Page 18 BSPT Die Page 4 BSPT
More informationDRV Magic Drill. High Efficiency Indexable Drill. Economical Inserts with 4 Cutting Edges and Excellent Chip Evacuation
DRV Magic Drill High Efficiency Indexable Drill Economical Inserts with 4 Cutting Edges and Excellent Chip Evacuation xd to 6xD drilling lineup with 4 chipbreakers for various machining applications High
More informationG02 CW / G03 CCW Circular Interpolation Motion (Group 01) - Mill
Haas Technical Documentation G02 CW / G03 CCW Circular Interpolation Motion (Group 01) - Mill Scan code to get the latest version of this document Translation Available G02 CW / G03 CCW Circular Interpolation
More informationMANUFACTURING TECHNOLOGY
MANUFACTURING TECHNOLOGY UNIT V Machine Tools Milling cutters Classification of milling cutters according to their design HSS cutters: Many cutters like end mills, slitting cutters, slab cutters, angular
More informationSpecial reamers. Figure N 1 Reamer with descending cutting edges in carbide (Cerin)
Special reamers There is a wide category of special reamers, ie non-standard, that are suitable to address particular problems encountered in the finishing holes, both for maintenance of individual pieces
More informationPROMOTIONS2016. Machining Intelligently. Self. ISCAR's Winning Edge Machining Innovations. ISCAR ENDUSERS
PROMOTIONS2016 ENDUSERS ISCAR's Winning Edge Machining Innovations Self Excellent Cylindricity and Superb Surface Finish! New Cutters Carrying Square Single-Sided Inserts Endmills with Indexable Solid
More informationBoring. Reaming. Burnishing. Threading. Drilling. Opening Drill. Large Diameter Replacable IC Insert Drilling System. Specials
oring Reaming urnishing Threading rilling Opening rill Large iameter Replacable I Insert rilling System Specials Opening rill Large iameter Replaceable I Insert rilling System iameter Range: 50.80mm -
More informationSPOTLIGHT 2018 METRIC
SPOTLIGHT 2018 METRIC Advanced Threading Solutions Innovative Grooving & Turning Solutions www.vargus.com Thread Turning External Toolholders with Coolant Thru Precise coolant thru, designed to efficiently
More informationTube Specialty Tools
Tube Specialty Tools Just as there are different reasons for finishing the cut ends of pipe or tubing, there are different tools and methods for doing the job. 1. Often, the only reason for finishing the
More informationHertel Indexable Drills (HID)
Hertel Indexable Drills (HID) mscdirect.com/hertel DESIGNED TO DELIVER Hertel cutting tools are designed to deliver consistency, reliability, durability and value with every cut. For over 65 years, Hertel
More informationSNAP. For more case studies, testimonials, and videos. We are also available on:
www.heuletool.com For more case studies, testimonials, and videos We provide online tool selectors for the COF,, DEF and BSF product groups. Simply enter your application information and the correct tool
More informationROOP LAL Unit-6 Lathe (Turning) Mechanical Engineering Department
Notes: Lathe (Turning) Basic Mechanical Engineering (Part B) 1 Introduction: In previous Lecture 2, we have seen that with the help of forging and casting processes, we can manufacture machine parts of
More informationCoroMill QD. High-security groove milling
CoroMill QD High-security groove milling The main challenge in groove milling is usually chip evacuation, especially when machining deep and narrow grooves. CoroMill QD is the first cutter of its kind
More informationDrilling. Drilling is the operation of producing circular hole in the work-piece by using a rotating cutter called DRILL.
Drilling Machine Drilling Drilling is the operation of producing circular hole in the work-piece by using a rotating cutter called DRILL. The machine used for drilling is called drilling machine. The drilling
More informationFigure 1: NC Lathe menu
Click To See: How to Use Online Documents SURFCAM Online Documents 685)&$0Ã5HIHUHQFHÃ0DQXDO 5 /$7+( 5.1 INTRODUCTION The lathe mode is used to perform operations on 2D geometry, turned on two axis lathes.
More information